Re: Question about ltspice .measure

"Svenn Are Bjerkem" <svenn.bjerkem@xxxxxxxxxxxxxx> schrieb im Newsbeitrag
news:1185737519.906350.166560@xxxxxxxxxxxxxxxxxxxxxxxxxxxxxxx
Hi,

I simulate a passive high-pass filter with a 1 pF capacitor and a 50
Ohm resistor.
I simulate reom 10 to 100 GHz
With the waveform tool I measure the -3 dB frequency to be 3.19 GHz
and then I tried to measure with a .measure statement from a file. The
measure statement I took from the manual:

.MEAS AC tmp max mag(V(out)); find the peak response
.MEAS AC meas_3db trig mag(V(out))=tmp/sqrt(2)

The measure report windos tell me:
tmp: MAX(V(out))=(-0.0043981dB,1.82317°) FROM 10 TO 1e+011
meas_3db=9.68205e+010 FROM 3.17955e+009 TO 1e+011

What is the number directly behind the =? (9.68205e+010)

Maybe the last before last frequency point in the AC-simulation.

Svenn#


Hello Svenn,

The following command will do what you want.

..ac dec 100 10k 100g

..MEAS AC tmp max mag(V(out)); find the peak response
..MEAS AC meas_3db when mag(V(out))=(tmp/sqrt(2))

--- output in the .log file
tmp: MAX(mag(v(out)))=(-0.0043981dB,0°) FROM 10 TO 1e+011
meas_3db: mag(v(out))=(tmp/sqrt(2)) AT 3.18011e+009

Best regards,
Helmut

LTspice user group:
http://tech.groups.yahoo.com/group/LTspice/


.